MIM can mold straight internal channels that run parallel to the mold opening direction, formed by a core pin pulled out along that direction or by two half-grooves closed at the parting line. A channel that bends out of that direction needs a side action, a collapsible core or a secondary operation, so bends and branches are usually machined or moved to another process, and a fully enclosed passage cannot be molded at all.
The boundary is geometric, not metallurgical. A passage is moldable when a rigid steel core can occupy the space and withdraw without dragging the green part, and when feedstock can flow around that core and still leave a part strong enough to survive debinding and sintering. What follows is which geometries qualify, how core pins constrain bore length and diameter, and how a molded passage is specified.
What MIM Can and Cannot Mold Internally
A straight bore is the base case: the core pin is anchored in one half of the tool, sealed against the other, and withdraws on opening without a side action. A through bore is the most robust version because the pin is supported at both ends while the cavity fills; a blind bore leaves it cantilevered, so it deflects more under injection pressure and needs a larger diameter or a shorter length to stay straight. Where a passage cannot follow the opening direction, two half-grooves closed at the parting line can form it, at the cost of a witness line inside the bore.
| Route | How the passage is formed | Where it fits | Main constraint |
|---|---|---|---|
| Molded through bore | Core pin supported in both tool halves | Oil ways, pin holes, bushing and spool bores | Pin aspect ratio; seal-off flash at both entries |
| Molded blind bore | Cantilevered pin withdrawn from one side | Blind locating holes, spring seats, sensor pockets | Pin deflection; depth limited by diameter |
| Half-grooves at the parting line | Groove cut in each half, closed to form a passage | Non-round or large sections that reject a full pin | Witness line and flash path inside the bore |
| Post-sinter drilling | Bore cut after sintering on a machined datum | Intersecting, stepped or tightly toleranced passages | Tool reach, alignment, burr control |
The hard limit is enclosure. A channel surrounded by metal with no opening in the opening direction gives the core no way out, and gives binder vapor no way out during debinding. That rules out the fully enclosed serpentine geometry that additive processes build. For a bent or branching path, the practical options are to mold straight segments and join them by machining or brazing, or to change process. The MIM versus binder jetting page treats internal channels as line-of-sight features and should be read as the consistent position.
Core Pin Aspect Ratio Sets How Long a Bore Can Run
Length-to-diameter ratio governs, because a slender pin bends under the lateral load of incoming feedstock, and a bent pin produces an eccentric bore or breaks. Published guidance commonly recommends through bores once the ratio exceeds about 4:1, so both pin ends are supported. For blind bores, one widely cited design guide puts roughly 3D as a preferred depth and around 5D as an upper screening limit, where D is bore diameter. These are screening values, not process guarantees: pin material, feedstock viscosity, wall section and tool stiffness all move the number, and a tool trial on the actual geometry is the only confirmation.
| Feature | Published screening guidance | Practical reading |
|---|---|---|
| Through bore, length-to-diameter | Through bores recommended above about 4:1 | Both pin ends supported; usual upper working range |
| Blind bore, depth | About 3D preferred; about 5D upper screening limit | D is bore diameter; confirm by tool trial |
| Fine passage, diameter | About 0.25 mm lower screening; 0.5 mm and above more practical | Supplier and feedstock dependent; below this, machine it |
| Wall around a channel | About 1-4 mm general; 1-6 mm or 1.0-3.0 mm cited as optimum | Uniformity matters more than the nominal figure |
| Intersecting passages | Not moldable as a single core | Mold one passage, machine the cross feature |
Bore diameter sets the other end of the window. One published process guide lists about 0.25 mm as a lower screening diameter and about 0.5 mm or larger as a more practical target, with fine features being supplier- and feedstock-dependent. Below that scale the pin is fragile enough to be damaged in handling or washed sideways by melt flow, and the annulus around it is small enough that fill becomes a short-shot risk. A design needing a 0.2 mm orifice usually gets it by drilling or laser processing after sintering.
Wall Section Around a Channel
The material between a channel and the outside surface is a ligament, and it fails in two ways: it breaks out during ejection or handling in the green state, or it distorts during sintering because mass on either side shrinks at different rates. Published wall guidance for conventional MIM parts is a general starting range of about 1-4 mm, with other guides citing roughly 1-6 mm as optimum and one convention giving about 0.040-0.120 in (approximately 1.0-3.0 mm). Uniformity matters more than any nominal value, which is the problem a channel creates: it removes mass from the middle of a section.
Two rules follow. Keep the ligament between bore and outer surface comparable to the wall thickness used elsewhere, and avoid placing a bore so it leaves a web much thinner than the rest of the section. When a passage must sit close to an outside face, expect the review to return either a larger outer dimension or a post-sinter machining step, because breakthrough and flash at a thin web are rejected in the green state. Spacing between adjacent bores follows the same logic: the web there is a ligament in compression during fill and in tension during shrinkage.
Debinding, Sintering Support and Bore Straightness
An internal passage does not protect itself in the furnace. Debinding removes binder through the open porosity of the compact, and surrounding section thickness sets how far vapor must travel, so a bore inside a thick ring debinds more slowly than the rest of the part. During sintering the part is weak and partially dense, and an unsupported span can sag. A flat support plane or stable contact geometry is preferred; where channel geometry prevents that, a dedicated setter is built as a tooling item with its own lead time, so it belongs in design review rather than the week before first article.
Straightness and roundness inherit the process window. As-sintered dimensions at Emitech hold ±0.3-0.5% of nominal dimension, about ±0.025 mm on features below 3 mm, and roughly ±0.01 mm after sizing or machining. A bore inside that band is achievable as molded; a shaft, spool or O-ring fit still has to be validated against the as-sintered band and surface condition, and commonly needs sizing or machining when roundness and straightness are what the fit depends on. Position to an outside datum deserves the same treatment, because a pin that shifts in the tool moves the whole passage.
Mold Reliability: Sealing, Venting and Ejection
A core pin must seal where it meets the opposite half, otherwise feedstock flashes into the bore mouth and the entry needs deburring. That seal-off is a wear point taking full injection pressure every cycle, and as it wears the flash ring at the bore entry grows. Venting follows the same geometry: the last place to fill in a core-pin cavity is usually the far end of the pin, and trapped air there produces a short shot or a burnt patch inside the passage where it cannot be polished out. Air venting at pin ends and inserts is discussed on the mold venting page; the design consequence is that a passage should not end in a closed pocket with no vent path.
Ejection is the third constraint. Green parts are brittle, so ejection force has to be carried by ribs, bosses or thick sections, and a bore wall is a poor place to push unless the pin lands on a ring thick enough to take the load. Where the passage is not aligned with the opening direction a side action is needed; those mechanisms add tooling cost, maintenance and cycle time, and their mechanics are covered on the undercut design page. Tool structure, cavity count, steel selection and maintenance intervals sit on the MIM tooling page.
Specifying and Verifying a Molded Passage
A drawing that says 'internal channel' leaves the supplier to guess the function. Specify what the passage has to do. For flow, state the medium, the temperature, and either a flow rate at a stated pressure drop or a pressure drop at a stated flow. For sealing, state a leak rate with method and limit, the subject of the MIM leak tightness page. For locating or clearance, state bore diameter with tolerance and the roundness or straightness the fit needs. Add allowable flash at the bore entry and the parting-line witness, plus a cleanliness requirement if debris can block the passage.
Verification follows the stated function rather than the appearance. A go/no-go ball or pin gauge proves minimum diameter at the entry, not the whole bore. A borescope reaches straight passages and shows flash and surface condition. Computed tomography cross-sections show internal geometry, wall thickness and shift in a way no external measurement can. A flow bench or pressure-decay rig proves the functional result, but it is fixture- and medium-specific, so a decay result does not transfer between gases, pressures or fixtures without recalibration. A passage that must also be leak tight needs the leak test kept separate from the flow test, because a bore that flows freely can still weep through interconnected porosity in the surrounding wall.
Frequently Asked Questions
Q: Can MIM mold a curved or branching channel that is fully enclosed?
Not if it is fully enclosed. Molding needs a core that withdraws or collapses, and debinding needs a path for binder vapor, so a passage that closes on itself has no valid tool. A passage that bends or branches away from the opening direction is moldable only with a side action or a collapsible core, which adds tooling cost, cycle time and maintenance; many designs instead mold straight segments and join them by machining or brazing, or move to an additive process that builds the passage as the part grows.
Q: What length-to-diameter ratio can a molded bore have?
Through bores are commonly recommended once the ratio exceeds about 4:1, because a pin supported at both ends stays straighter. Blind bores are usually held to roughly 3D, with about 5D quoted as an upper screening limit. Both are screening numbers from design guides: pin material, feedstock, wall section and tool stiffness change the answer, and a tool trial is the only confirmation.
Q: How small a bore can be molded?
One published process guide lists about 0.25 mm as a lower screening diameter and about 0.5 mm and larger as a more practical target. In practice the limit is pin fragility and whether feedstock can fill the annulus at the required pressure. Below the practical target, the lower-risk route is to mold without the passage and drill or laser it after sintering.
Q: How much material do I need between a channel and the outside surface?
There is no universal minimum; published guidance runs from about 1-4 mm as a general starting range to roughly 1-6 mm or 1.0-3.0 mm as optimum. The controlling issue is the ligament: thick enough to survive ejection in the green state, and uniform enough around the bore that shrinkage does not distort it. A bore leaving a web much thinner than the rest of the part should expect a design change.
Q: When is molding a channel the wrong choice?
Molding is not recommended when the passage is fully enclosed, when a bend or cross feature would need a side action whose tooling and maintenance are not economic at the volume, when the bore must hold a shaft or spool fit tighter than the as-sintered band, when volume is too low to justify a core pin, or when the surrounding wall would be a thin web. Post-sinter drilling, a machined insert or brazing straight segments is then more reliable, and the leak requirement should be written before the process is chosen.
A molded internal channel depends on three constraints that must agree: a core that can withdraw, a wall that carries the bore through ejection and sintering, and a drawing that states flow or seal function rather than the feature name. When any one is missing, the passage is better machined after sintering than molded.
Send the part drawing with the passage path, bore diameter and function, wall section, and any leak or flow requirement through the contact page. Emitech works to ISO 9001:2015 across a 0.1-200 g part range, with as-sintered tolerances of ±0.3-0.5% of nominal dimension and about ±0.025 mm on features below 3 mm. Core pin design, minimum bore and channel parameters are quoted on request, normally within 24 hours; tooling is typically 15-20 days from drawing approval and production 4-6 weeks after mold approval.
Precision Metal Parts from Emitech
Nanjing Emitech delivers MIM, CNC machining, and custom metal parts. MIM services · Request a quote

